Crossprobe

USB-C power input (5 V, USB 2.0)

A USB-C receptacle for a device that takes 5 V from a USB-C source and uses USB 2.0 data: the two 5.1 kΩ pull-downs on CC1 and CC2, the VBUS, ground and data pins bussed as the Type-C specification requires, and the unused SBU pins left open.

Draft Connector 3 parts Apache-2.0

Draft. Nobody has checked this against the datasheet yet. It follows USB Type-C Cable and Connector Specification, Release 2.0 (August 2019), KiCad opens it without errors, and the nets match the specification. Check the values yourself before you build it.

Open in Crossprobe Download for KiCad (.zip)

Schematic of the USB-C power input (5 V, USB 2.0), drawn in KiCad
The schematic as KiCad draws it. Open it at full size to zoom: it is a vector image.

Pins used on USB-C receptacle

Pin numbers follow the datasheet's pin table. Every other pin is marked no-connect (X), so you can see what is free; delete the marker to use a pin.

PinName in KiCadNet
A1GNDGND
A4VBUSVBUS
A5CC1Net-(J1-CC1)
A6D+USB_DP
A7D-USB_DM
A9VBUSVBUS
A12GNDGND
B1GNDGND
B4VBUSVBUS
B5CC2Net-(J1-CC2)
B6D+USB_DP
B7D-USB_DM
B9VBUSVBUS
B12GNDGND
SHSHIELDGND

Checklist

Required

Recommended

Good to know

PCB layout

3 footprints, 10 tracks and 2 vias, drawn for KiCad and checked with its design rule check and schematic comparison. The block has no board outline: it takes the one of the board you place it on.

PCB layout of the USB-C power input (5 V, USB 2.0), drawn in KiCad
The layout as KiCad draws it: front copper red, back copper blue.

Parts list

RefValueKiCad symbolFootprintSource
J1USB-C receptacleConnector:USB_C_Receptacle_USB2.0_16PConnector_USB:USB_C_Receptacle_HRO_TYPE-C-31-M-12USB 3.0 Promoter Group, p. 69, Table 3-5, receptacle pin assignments for USB 2.0-only support
R15.1kDevice:RResistor_SMD:R_0402_1005MetricUSB 3.0 Promoter Group, p. 236, Table 4-25, Rd 5.1 kOhm
R25.1kDevice:RResistor_SMD:R_0402_1005MetricUSB 3.0 Promoter Group, p. 236, Table 4-25, Rd 5.1 kOhm

How to use it

In KiCad 9 or later. Unzip the download. Open Preferences › Manage Design Block Libraries, add the unzipped crossprobe.kicad_blocks folder as a library, then place the block from the design block chooser. The symbols and footprints are KiCad's own.

In Crossprobe. Choose Open in Crossprobe above. It opens a new project with this block already in its schematic, using the reference designators from the table above. The project stays in your browser until you save it, and you pick where it goes. To add the block to a project you already have, open that project, turn on Edit and use Add block.

Source

USB Type-C Cable and Connector Specification, Release 2.0 (August 2019), USB 3.0 Promoter Group. Page numbers on this page refer to that version of the document. Page numbers are the PDF's. Requirements are quoted as facts, with page numbers; the circuit is drawn here, not copied.

This block's files and spec are on GitHub in Crossprobe-AI/kicad-design-blocks (Apache-2.0). Found a wrong value? Open an issue with the page it should come from.

More: the KiCad design review checklist, or all design blocks.